Milling A Contour Pocket - Cycle63 - Siemens Sinumerik 840D sl Programming Manual

Programming cycles externally
16.1 Technology cycles
16.1.29

Milling a contour pocket - CYCLE63

Programming
CYCLE63(STRING[100] _PRG, INT _VARI, REAL _RP, REAL _Z0, REAL _SC,
REAL _Z1, REAL _F, REAL _FZ, REAL _DXY, REAL _DZ, REAL _UXY, REAL
_UZ, INT _CDIR, REAL _XS, REAL _YS, REAL _ER, REAL _EP, REAL _EW,
REAL _FS, REAL _ZFS, STRING[20] _TR, INT _DR, INT _UMODE, INT _GMODE,
INT _DMODE, INT _AMODE)
Parameters
No. Param Mask Param intern
1
PRG _PRG
2
_VARI
3
RP _RP
4
Z0 _Z0
5
SC _SC
6
Z1 _Z1
7
F _F
8
FZ _FZ
9
DXY _DXY
10
DZ _DZ
11
UXY _UXY
12
UZ _UZ
13
_CDIR
796
Explanation
Name of removal program
Machining type
UNITS: Machining process
1 = Roughing
3 = Finishing of base
4 = Finishing of edge
5 = Chamfer
TENS: Infeed type
0 = Center insertion
1 = Helical insertion
2 = Oscillating insertion
HUNDREDS: Reserved
THOUSANDS: Lift mode
0 = Lift off to retraction plane
1 = Lift off to reference point + safety clearance
TEN THOUSANDS: Start point for roughing and finishing base
0 = Auto
1 = Manual
Retraction plane (abs)
Reference point of tool axis (abs)
Safety clearance (to be added to reference point, enter without sign)
Final depth (see _AMODE UNITS)
Feedrate in the plane during roughing/finishing
Depth infeed rate
Infeed plane - unit (see AMODE TENS)
Depth infeed
Finishing allowance, plane
Finishing allowance, depth
Milling direction
0 = Climbing
1 = Conventional
Programming Manual, 02/2011, 6FC5398-2BP40-1BA0
Job planning