Extended Stock Removal Cycle - Cycle950 (Sw 5.3 And Later) - Siemens SINUMERIK 840D Programming Manual

Turning Cycles
4

4.10 Extended stock removal cycle - CYCLE950 (SW 5.3 and later)

4.10 Extended stock removal cycle - CYCLE950 (SW 5.3 and later)
The extended stock removal cycle is an option.
It requires SW 5.3 in the NCK and MMC.
Programming
CYCLE950 (_NP1, _NP2, _NP3, _NP4, _VARI, _MID, _FALZ, _FALX, _FF1, _FF2,
_FF3, _FF4, _VRT, _ANGB, _SDIS, _NP5, _NP6, _NP7, _NP8, _APZ, _APZA, _APX,
_APXA, _TOL1)
Parameters
_NP1
string
_NP2
string
_NP3
string
_NP4
string
_VARI
int
_MID
real
_FALZ
real
_FALX
real
_FF1
real
4-260
Name of the contour subroutine for the finished part contour
Label / block number start of finished part contour, optional
(this can be used to define contour sections)
Label / block number end of finished part contour, optional
(this can be used to define contour sections)
Name of the stock removal program to be generated
Type of machining : (enter without sign)
ONES DIGIT:
Values: 1...Longitudinal
2...Face
3...Parallel to contour
TENS DIGIT:
Values: 1...Programmed infeed direction X-
2...Programmed infeed direction X+
3...Programmed infeed direction Z-
4...Programmed infeed direction Z+
HUNDREDS DIGIT:
Values: 1...Roughing
2...Finishing
3...Complete
THOUSANDS DIGIT:
Values: 1...With Rounding
2...Without Rounding (liftoff)
TEN THOUSANDS DIGIT:
Values: 1...Machine relief cuts
2...Do not machine relief cuts
HUNDRED THOUSANDS DIGIT:
Values: 1...Programmed machining direction X-
2...Programmed machining direction X+
3...Programmed machining direction Z-
4...Programmed machining direction Z+
Infeed depth (enter without sign)
Final machining allowance in the longitudinal axis (enter without sign)
Final machining allowance in the facing axis (enter without sign)
Feedrate for longitudinal roughing
SINUMERIK 840D/840Di/810D/FM-NC Programming Guide, Cycles (PGZ) - 04.00 Edition
03.96
04.00
4
 Siemens AG 2000 All rights reserved.