Program Support Functions; Changing Of Tool Offset Value Programmable Data Input (G10) - Siemens Sinumerik 802D sl Programming Manual

04.07
4.2

Program support functions (2)

4.2.1 Changing of tool offset value
Programmable data input (G10)
By using the commands of "G10 P⋅⋅⋅ X(U)⋅⋅⋅ Y(V)⋅⋅⋅ Z(W)⋅⋅⋅ R(C)⋅⋅⋅ Q ;",
it is possible to write and update the tool offset amount using a part program. If an
address is omitted in the designation of data input block, the offset amounts for the
omitted addresses remains unchanged.
Table 4-6
Address
P
X
Y
Z
U
V
W
R
C
Q
Address P
Address P specifies the tool offset number and, at the same time, whether tool
geometry offset or tool wear offset is to be changed. The value to be specified with
address P depends on the setting of MD $MC_EXTERN_FUNCTION_MASK, Bit1
as follows:
$MC_EXTERN_FUNCTION_MASK, Bit1 = 0
P1 to P99:
P100 + (1 to 1500):
$MC_EXTERN_FUNCTION_MASK, Bit1 = 1
P1 to P9999:
P10000 + (1 to 1500):
© SIEMENS AG 2007 All rights reserved
SINUMERIK 802D sl/840D sl840D/840Di sl/840Di/810D ISO Turning -- 04.07 Edition
Description of addresses
Offset number (see explanation below)
Offset value on X axis (absolute, incremental)
Offset value on Y axis (absolute, incremental)
Offset value on Z axis (absolute, incremental)
Offset value on X axis (incremental)
Offset value on Y axis (incremental)
Offset value on Z axis (incremental)
Tool nose radius offset value (absolute)
Tool nose radius offset value (incremental)
Imaginary tool nose number
Writing tool wear offset
Writing tool geometry offset
Writing tool wear offset
Writing tool geometry offset
Enhanced Level Commands
4.2 Program support functions (2)
Description
4-129