Geometry Settings - Siemens Sinumerik 840D sl Programming Manual

Geometry settings

9.1 Settable zero offset (G54 to G57, G505 to G599, G53, G500, SUPA, G153)
Example
Program code
N10 G0 G90 X10 Y10 F500 T1
N20 G54 S1000 M3
N30 L47
N40 G55 G0 Z200
N50 L47
N60 G56
N70 L47
N80 G53 X200 Y300 M30
Further information
A parameterized zero offset is in principle a set frame (Page 305). Consequently, the following
components and frame values are also available for a parameterized zero offset:
● Offset
● Rotation
● Scaling
● Scale
138
Three workpieces that are arranged on a pallet in
accordance with the zero offset values G54 to
G56 are to be machined in succession. The ma‐
chining sequence is programmed in subprogram
L47.
Comment
; Approach
; Call of the first WO, spindle clockwise
; Program pass as subprogram
; Call of the second WO, Z via obstruction
; Program pass as subprogram
; Call of the third WO
; Program pass as subprogram
; Suppress zero offset, end of program
Programming Manual, 01/2015, 6FC5398-1BP40-5BA2
Fundamentals