Programming Example - Siemens SINUMERIK 840D sl Programming Manual

6.2.2.2

Programming example

Calibrate tool probe (machine-related)
Tool probe 1 is stationary but provides a switching signal. The calibration tool is inserted in
the turret as tool T7.
Values of the calibration tool T7 D1:
Tool type (DP1):
Cutting edge length (DP2):
Length 1 - geometry (DP3).
Length 2 - geometry (DP4):
Radius - geometry (DP6):
This radius must be taken into account in
selecting the starting position for calibration
of _TP[0,1], _TP [0,3] (increase distance
from probe by 2 × R).
Values of tool probe 1 in data block GUD6
which were determined manually to 5 mm
accuracy beforehand (relative to the
machine zero):
_TP[0,0] = 50
_TP[0,1] = 20
_TP[0,2] = 70
_TP[0,3] = 40
To obtain a minimum measurement path of 1 mm, the measurement path is programmed
with _FA = 1+5= 6 mm (max. total measurement path = 12 mm).
%_N_CALIBRATE_MTT_MPF
N05 G94 G90 DIAMOF
N10 T7 D1
N15 G0 SUPA Z300 X240
N20 _TZL=0.001 _PRNUM=1 _VMS=0 _NMSP=1
N21 _MVAR=0 _MA=2 _TSA=5 _FA=6
N30 CYCLE982
N35 G0 SUPA Z60
N38 _MA=1
N40 CYCLE982
N45 G0 SUPA X20
N48 _MA=2
N50 CYCLE982
N55 G0 SUPA Z0
N58 _MA=1
Measuring cycles
Programming Manual, Release 04/2006, 6FC5398-4BP10-0BA0
Measuring Cycles for Turning Machines
6.2 CYCLE982, CYCLE972 Tool: Measure turning tools
500
3
L1 = 10
L2 = 40
R = 5
;Calibration tool
;Starting position in minus X
direction,
;procedure when ZO is deactivated
;Parameters for calibration cycle
;Calibration in minus X direction
;Approach new starting position
;Select another measuring axis
;Calibration in minus Z direction
;Approach new starting position
;Calibration in plus X direction
;Approach new starting position
6-9