Groove - Cycle930 - Siemens SINUMERIK 840D sl Programming Manual

Programming cycles externally
18.1 Technology cycles
No. Param Param
mask internal
18.1.31

Groove - CYCLE930

Programming
CYCLE930(REAL _SPD, REAL _SPL, REAL _WIDG, REAL _WIDG2, REAL _DIAG,
REAL _DIAG2, REAL _STA, REAL _ANG1, REAL _ANG2, REAL _RCO1, REAL
_RCI1, REAL _RCI2, REAL _RCO2, REAL _FAL, REAL _IDEP1, REAL _SDIS,
INT _VARI, INT _DN, INT _NUM, REAL _DBH, REAL _FF1, INT _NR, REAL
_FALX, REAL _FALZ, INT _DMODE, INT _AMODE)
Parameters
No. Param Param
mask internal
1 X0 _SPD
2 Z0 _SPL
3 B1 _WIDG
B2 _WIDG2
4
T1 _DIAG
5
6 T2 _DIAG2
α0 _STA
7
8 α1 _ANG1
9 α2 _ANG2
10 R1/FS1 _RCO1
11 R2/FS2 _RCI1
R3/FS3 _RCI2
12
R4/FS4 _RCO2
13
14 U _FAL
15 D _IDEP1
16 SC _SDIS
694
Explanation
ONE MILLION: Radius/chamfer 3
0 = Radius
1 = Chamfer
Explanation
Reference point in the plane axis (always diameter)
Reference point along the longitudinal axis
Width at bottom of groove
Width at top of groove (for interface only)
Depth of groove at the reference point
for abs and longitudinal machining = diameter, otherwise inc
Groove depth opposite the reference point (for interface only),
for abs and longitudinal machining = diameter, otherwise inc
Angle of inclination (-180 ≤ _STA ≤ 180)
Side angle 1 (0 ≤ _ANG1 < 90) at the side of the groove determined by the reference point
Side angle 2 (0 ≤ _ANG2 < 90) opposite the reference point
Rounding radius or chamfer width 1, external at the reference point
Rounding radius or chamfer width 2, internal at the reference point
Rounding radius or chamfer width 3, internal opposite the reference point
Rounding radius or chamfer width 4, external opposite the reference point
Finishing allowance in X and Z, see _VARI (TEN THOUSANDS) (to be entered without
sign)
Maximum depth infeed on insertion (enter without sign)
0 = 1st cut directly to full depth
> 0 = 1st cut_IDEP1, 2nd cut 2 · _IDEP1 etc.
Safety clearance (enter without sign)
Programming Manual, 03/2013, 6FC5398-2BP40-3BA1
Job Planning